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Bend sheet plate (to known diameter)
- Thread starter intogtar
- Start date
MrCATIA
Super Moderator
The easiest way for a simple part like this is to use the Sheetmetal workbench.
Can you please tell what exact tools should I use to get my flat plate with holes to the round one?
Thank you!
MrCATIA
Super Moderator
Sorry, but I don't have access to CATIA right now and can't verify all the exact steps.
If you know how to use the Sheetmetal workbench, the process is fairly simple:
1. define the curved plate
2. unfold (flatten) the part, and add the holes
3. fold the part (with the holes) back to it's curved shape
If you're new to CATIA, I suggest you get some training.
If you know how to use the Sheetmetal workbench, the process is fairly simple:
1. define the curved plate
2. unfold (flatten) the part, and add the holes
3. fold the part (with the holes) back to it's curved shape
If you're new to CATIA, I suggest you get some training.
MrCATIA
Super Moderator
OK Intogtar, here's the exact steps: (based on CATIA V5, R18)
1. Use the Generative Sheetmetal workbench (SMD license), and start by using the SheetMetal Parameters to define wall thickness and other material properties
2. Create a Sketch of the side profile of the the curved plate, with bend radius and enclosed angles
3. INSERT + ROLLED WALLS + ROLLED WALL, select profile sketch, and speciafy the length of plate
4. INSERT + VIEWS + FOLD/UNFOLD to see flat, developed shape
5. With unfolded (flat) shape;
5a. create a sketch of the hole
5b. INSERT + CUTTING + CUT OUT, and select sketch of the hole
5c. INSERT + VIEWS + FOLD/UNFOLD to see curved plate with deformed hole
repeat for more holes
6. With folded (curved) shape;
6a. create a sketch of a another hole
6b. INSERT + CUTTING + CUT OUT, and select sketch of hole
6c. INSERT + VIEWS + FOLD/UNFOLD to see flat plate with this hole developed in flat
7. to make a drawing view of the developed (unfolded) plate, use the UNFOLDED VIEW tool in the Drafting workbench and add dimensions
1. Use the Generative Sheetmetal workbench (SMD license), and start by using the SheetMetal Parameters to define wall thickness and other material properties
2. Create a Sketch of the side profile of the the curved plate, with bend radius and enclosed angles
3. INSERT + ROLLED WALLS + ROLLED WALL, select profile sketch, and speciafy the length of plate
4. INSERT + VIEWS + FOLD/UNFOLD to see flat, developed shape
5. With unfolded (flat) shape;
5a. create a sketch of the hole
5b. INSERT + CUTTING + CUT OUT, and select sketch of the hole
5c. INSERT + VIEWS + FOLD/UNFOLD to see curved plate with deformed hole
repeat for more holes
6. With folded (curved) shape;
6a. create a sketch of a another hole
6b. INSERT + CUTTING + CUT OUT, and select sketch of hole
6c. INSERT + VIEWS + FOLD/UNFOLD to see flat plate with this hole developed in flat
7. to make a drawing view of the developed (unfolded) plate, use the UNFOLDED VIEW tool in the Drafting workbench and add dimensions
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MrCATIA
Super Moderator
Notes on my last post:
1. The icons can be also be used for the all the steps. I listed the INSERT menu commands because they are easier to type in a posting like this.
2. I used CUTOUTS and sketches to define the round holes. The HOLE command can also be used.
3. I used the Generative SheetMetal workbench (not the Part Design Workbench) to build the solid model. Note the different features in the tree, and also the different set of icon commands:
I tried to identify each feature with a different color, but it's difficult to see - sorry
4. This part could be done with other CATIA methods - I think this was the quickest and easiest.
5. I found out there is a limit of 5 images that can be inserted in these posts.
1. The icons can be also be used for the all the steps. I listed the INSERT menu commands because they are easier to type in a posting like this.
2. I used CUTOUTS and sketches to define the round holes. The HOLE command can also be used.
3. I used the Generative SheetMetal workbench (not the Part Design Workbench) to build the solid model. Note the different features in the tree, and also the different set of icon commands:
I tried to identify each feature with a different color, but it's difficult to see - sorry
4. This part could be done with other CATIA methods - I think this was the quickest and easiest.
5. I found out there is a limit of 5 images that can be inserted in these posts.
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